Abstract
Based on ANSYS APDL, this paper simulates the welding process of the safety end of the pipe using different heat source models. The results show that the shape of the moving heat source under the body heat rate heat source model and the double ellipsoid heat source model is ellipsoidal shape. The body heat rate heat source has a larger high temperature area than the double ellipsoidal heat source. The variation law of temperature field and stress field is basically the same, but the overall stress field under double ellipsoid heat source load is about 20 MPa smaller than the total stress field under body heating rate. The comparison of different heat source models can provide some help for the numerical simulation of welding.
You have full access to this open access chapter, Download conference paper PDF
Keywords
1 Introduction
Welding process is a key process in the manufacture and production of nuclear power pressure equipment, in the nuclear power plant primary circuit system, there are many nozzle safety ends, mainly including the hot section and cold section on the reactor pressure vessel to take over the safety end, the fluctuating tube on the regulator to take over the safety end, etc., the corresponding geometry, materials, welding processes are generally similar [1,2,3]. It has been observed that the coupling of residual stress formed after welding and service load will accelerate the stress corrosion phenomenon of components, promote the germination and propagation of cracks, and thus threaten the safe operation of nuclear power plants. Therefore, it is necessary to pay close attention to the residual stress changes of the welded joint [4, 5].
In the current research, there are few three-dimensional overall simulations of welded joints at the safety end of the pipe. In the process of welding temperature field calculation, the correct selection of heat source model is an important guarantee for the accuracy of the calculation results [6, 7]. Based on ANSYS APDL, this paper simulates the welding safety end of the joint by using ellipsoid heat source and body heat rate heat source model, and analyzes the changes of welding temperature field and stress field.
2 Geometry and Meshing
The object studied in this paper is the model of welded joints of the safety end of the pressure vessel of the primary circuit reactor of nuclear power plants, with a total length of 1628.7 mm, an inner and outer radius of 417.3 mm and 500.3 mm, respectively, and a single-sided V-shaped groove with an angle of 15°. In addition, considering the calculation of the three-dimensional model, it is necessary to simplify the weld part reasonably, and relevant studies have shown that for the simulation of multi-pass welding problems, the intermediate process has little effect on the residual stress, therefore, under comprehensive consideration, the total weld area is divided into 11 layers, and the thickness of the weld in the cover welding stage at the end of the welding is 11.5 mm, and the rest are 8 mm, as shown in Fig. 1. In this paper, the thermal–mechanical indirect coupling is used for simulation, the solid70 unit is selected for thermal analysis, and the structural analysis is converted to the solid185 unit by etchg, tts command. The meshing adopts a combination of mapping surface mesh and sweep mesh, which is easier to obtain a good quality hexahedral mesh, the weld and heat affected zone are the places with the highest degree of mesh fineness, and the base metal area can be properly coarseened for computational efficiency, as shown in Fig. 2.
3 Welding Process and Heat Source Model
According to the welding process of nuclear power equipment, for the welding joint of the safety end of the pipe with isolation layer, the preheating treatment is generally not done before welding, and the temperature between the welding layers is controlled at 100–200 °C, and the excessive interlayer temperature will adversely affect the nickel-based alloy. In this simulation, the welding speed is set to 20 mm/s, the current is set to 630 A, and the voltage is set to 35 V. The main driving factor for the welding process to proceed is determined by the welding heat source, which causes phase changes, thermal strains, thermal stresses. For welding engineering applications, Gaussian surface heat source, double ellipsoidal heat source, bulk heat rate model, conical heat source, and strip heat source are commonly used [8, 9]. For large cylindrical models, the double ellipsoidal heat source model and the bulk heat rate model are usually used in the numerical simulation of welding, and the expression is as follows. The shape parameters of the double ellipsoid heat source have a great influence on the temperature field, and it is necessary to obtain the ideal parameters through repeated experiments [10], and \({a}_{f}\) = 8 mm, \({a}_{r}\) = 12 mm, b = 10 mm, c = 11.5 mm are used in this paper.
In Eqs. (1) and (2), q is the heat generation rate, w m-3; af, ar, b, c are the shape parameters of the double ellipsoidal heat source, m; ff and fr are the energy distribution coefficients before and after the heat source model, where HGEN represents the bulk heat generation rate (w/m3), K represents the welding efficiency, A represents the weld cross-sectional area (m2), V represents the welding speed (m/s), and DT represents the time step size of each substep (s).
4 Results and Discussions
4.1 Comparison of Welding Temperature Field Analysis Results
Two different heat source models are used as heat load inputs and analyzed using Ansys apdl. Because of the large number of weld layers, Only the temperature field distribution of the first and last welds are captured in this paper, the results are shown in the Figs. 3 and 4. From the temperature field analysis results, it can be seen that the welding heat source center moves continuously along the circumferential direction of the weld. The temperature is the highest from the welding heat source center and the heat gradient is distributed in an ellipsoidal shape. The welding time of each weld is set to 157 s, and the cooling time of 10,000 s is set after welding is completed to cool it to room temperature.
Comparing the instantaneous temperature field of the two bulk heat source models at the same time, the temperature field distribution trend is basically the same. Due to the combined effect of heat conduction and heat source movement, the temperature field of the high temperature zone of the bulk heat rate model is also ellipsoidal, so the shape of the two molten pools is basically similar. From the temperature field of the first weld, the highest temperature under the action of the body heat rate model is 1595 °C, the highest temperature under the action of the double ellipsoidal heat source is 1513 °C. The maximum temperature in the high temperature area is about 60 °C higher than that of the double ellipsoid heat source because the energy of the body heat rate heat source is more concentrated. This is shown in Figs. 5 and 6, from the temperature field of the last weld, the maximum temperature is reduced due to the reduction of the interlayer temperature during the welding process, and the effect of the double ellipsoid heat source is more obvious from the figure.
4.2 Analysis and Comparison of Welding Stress Field Results
When performing stress field analysis, it is necessary to fix constraints on both ends of the welded joint, otherwise there will be a situation where the calculation does not converge. The calculation results of the temperature field of the two are taken as the thermal load, that is, read the.rth file, and the *do cycle statement is also used to apply it one by one, and finally obtain the welding residual stress after the cooling of the two. As shown in the Figs. 7 and 8, the overall welding residual stress size when using double ellipsoid heat source is 395 MPa, and the welding residual stress size when using bulk heat rate heat source is 417 MPa, the difference between the two is about 20 MPa, indicating that the use of different heat sources has a certain impact on the welding residual stress field, but the residual stress distribution of the two is basically the same. The stress at the weld and the heat-affected zone is large, and the stress influence at the base metal away from the weld is small. Select the 0° direction as the path to observe the distribution of welding residual stress after the cooling of the entire welded joint. As can be seen from Fig. 9, the peak residual stress after cooling is located at the junction of the weld and the base metal, and the stress gradually decreases far from the weld.
5 Conclusion
Based on the results and discussions presented above, the conclusions are obtained as below:
-
(1)
The double ellipsoid heat source model needs to determine the shape parameters according to the actual situation of the molten pool, while the body heat rate heat source model is more efficient.
-
(2)
The shape of the molten pool of the double ellipsoid heat source and the body heat rate heat source is ellipsoid and the size is basically the same. The overall stress field under the action of body heat rate heat is about 20 MPa higher than that of the double ellipsoid heat source, and the stress field distribution law of the two is the same.
-
(3)
Double ellipsoidal heat source and bulk heat rate heat source have advantages and disadvantages when simulating the welding process of the safety end. More heat source models can be tried for comparative analysis and better heat source models can be selected.
References
Guo R, Xue H, Gong XY (2018) Influence of residual stress and heterogeneity on mechanical field at crack tips in safety end of nuclear power plant. Procedia Struct Integr 13:2203–2209
Wang HT, Wang GZ, Xuan FZ (2013) Fracture mechanism of a dissimilar metal welded joint in nuclear power plant. Eng Fail Anal 28:134–148
Li G, Lu XF, Zhu XL (2017) The defects and microstructure in the fusion zone of multipass laser welded joints with Inconel 52 M filler wire for nuclear power plants. Opt Laser Technol 94:97–105
Kim KS, Lee HJ, Lee BS et al (2009) Residual stress analysis of an Overlay weld and a repair weld on the dissimilar Butt weld. Nucl Eng Des 239(12):2771–2777
Song TK, Kim YB, Kim YJ et al (2014) Prediction of welding residual stress profile in dissimilar metal Nozzle Butt weld of nuclear power plant. Procedia Mater Sci 3:784–789
Dornelas PHG, Filho JDCP, Oliveira VHPME et al (2021) Studying the influence of the interpass temperature on the heat-affected zone of an API 5L X65 steel welded pipe joint through computational and physical simulations. Int J Press Vessels Pip 194B:104548
Xie Y, Zhuang J, Huang B et al (2020) Effect of different welding parameters on residual stress and deformation of 20/0Cr18Ni9 dissimilar metal arc-welding joint. J Adhes Sci Technol 34(6):1–25
Gao ZH, Han B, Li LY et al (2022) Numerical simulation of residual stress in post internal welding process of bimetal composite pipe and optimization of welding sequence. Int J Press Vessels Pip 199:104730
Zala AB, Jamnapara NI, Sasmal CS et al (2022) Study of microstructure & mechanical properties of TIG welded aluminized 9Cr-1Mo steel. Fusion Eng Des 176:113038
Lu Y, Zhu S, Zhao Z, et al (2020) Numerical simulation of residual stresses in aluminum alloy welded joints. J Manuf Process 50:380–393
Acknowledgements
This work was financially supported by the Applied Research Project of National Natural Science Foundation of China under Grant (No. 52175343).
Author information
Authors and Affiliations
Corresponding author
Editor information
Editors and Affiliations
Rights and permissions
Open Access This chapter is licensed under the terms of the Creative Commons Attribution 4.0 International License (http://creativecommons.org/licenses/by/4.0/), which permits use, sharing, adaptation, distribution and reproduction in any medium or format, as long as you give appropriate credit to the original author(s) and the source, provide a link to the Creative Commons license and indicate if changes were made.
The images or other third party material in this chapter are included in the chapter's Creative Commons license, unless indicated otherwise in a credit line to the material. If material is not included in the chapter's Creative Commons license and your intended use is not permitted by statutory regulation or exceeds the permitted use, you will need to obtain permission directly from the copyright holder.
Copyright information
© 2024 The Author(s)
About this paper
Cite this paper
Chen, W., Ji, D. (2024). Simulation and Comparative Analysis of Welding of the Safety End of the Pipe Based on Different Body Heat Source Models. In: Halgamuge, S.K., Zhang, H., Zhao, D., Bian, Y. (eds) The 8th International Conference on Advances in Construction Machinery and Vehicle Engineering. ICACMVE 2023. Lecture Notes in Mechanical Engineering. Springer, Singapore. https://doi.org/10.1007/978-981-97-1876-4_105
Download citation
DOI: https://doi.org/10.1007/978-981-97-1876-4_105
Published:
Publisher Name: Springer, Singapore
Print ISBN: 978-981-97-1875-7
Online ISBN: 978-981-97-1876-4
eBook Packages: EngineeringEngineering (R0)